1 / 42

Demo of FLUENT in Workbench

Demo of FLUENT in Workbench. André Bakker April 24, 2009. Purpose of demo. Set up and solve a FLUENT system in Workbench, showing these steps: Geometry import with parametric modifications, flow volume extraction, splitting for symmetry. Set up and solve in FLUENT.

ince
Télécharger la présentation

Demo of FLUENT in Workbench

An Image/Link below is provided (as is) to download presentation Download Policy: Content on the Website is provided to you AS IS for your information and personal use and may not be sold / licensed / shared on other websites without getting consent from its author. Content is provided to you AS IS for your information and personal use only. Download presentation by click this link. While downloading, if for some reason you are not able to download a presentation, the publisher may have deleted the file from their server. During download, if you can't get a presentation, the file might be deleted by the publisher.

E N D

Presentation Transcript

  1. Demo of FLUENT in Workbench André Bakker April 24, 2009

  2. Purpose of demo • Set up and solve a FLUENT system in Workbench, showing these steps: • Geometry import with parametric modifications, flow volume extraction, splitting for symmetry. • Set up and solve in FLUENT. • Review results in CFD-Post. • Show to methods to perform parametric analysis: • Using the duplicate option. • Using a design points table.

  3. Example case • Perform parametric analysis showing performance as a function of inlet pipe length and velocity at the side inlet. • Static mixer geometry created in GAMBIT. • Exported as Parasolid file. • One main inlet, a side inlet, and an outlet. • The depth that the side inlet sticks into the main pipe will be parameterized in DM. • Will solve flow field and temperature field for two streams with different inlet temperature mixing. • Calculate mixing efficiency with expression language in CFD-Post.

  4. Demonstration

  5. Create fluid flow system • Start WB. • Create a FLUENT system named “Chemical Mixer”. • Geometry → import → mixer-sideinlet-inside.x_t. • Geometry → Edit.

  6. Extrude side pipe (1/4) • Create → New Plane. • Details View → Type → From Face. • Click on Not selected.

  7. Extrude side pipe (2/4) • Click on face at end of pipe. • Apply. • Generate.

  8. Extrude side pipe (3/4) • Click Extrude icon. • Change FD1, Depth (>0) from 1m to 0.05m. • Click checkbox next to FD1. • Keep default parameter name.

  9. Extrude side pipe (4/4) • Click Generate. • Exruded pipe is now generated.

  10. Close inlets and outlet (1/2) • Use Concept → Surfaces from edges to close the inlet and outlet openings. • Select the three edges shown (hold ctrl key while selecting).

  11. Close inlets and outlet (2/2) • Click apply and generate. • Three transparent faces are created as shown. • To extract flow volume: Tools → Fill.

  12. Extract flow volume • Change Extraction Type from By Cavity to By Caps. • Click Generate. • Select new item Fill1 in tree Outline. • Highlights flow volume.

  13. Split for symmetry (1/3) • To split geometry: Tools → Symmetry. • Select XYPlane in Tree Outline. • Click Apply, then Generate.

  14. Split for symmetry (2/3) • In Tree Outline, expand “2 Parts, 2 Bodies”. • Right-click on Solid. • Rename this to Fluid.

  15. Split for symmetry (3/3) • In Tree Outline, switch back and forth between Part 1 and Fluid (under “2 Parts, 2 Bodies) to show the solid part and the flow volume. • Close DM.

  16. Show design point table • In WB, you can double click on the Parameter Set bar. The parameter setting the length of the inlet pipe will be shown. • Close the tables.

  17. Meshing – suppress solid • In WB: Mesh → Edit. • In Outline, volume.1 is the solid part and fluid is the flow volume. • Select Part 1, right-click and Suppress body.

  18. Named selection - Symmetry • Select the four symmetry surfaces, right click, Named Selection → name as “symmetry”.

  19. Named selection - inlets • Name large inlet as “inlet-main” and small inlet as “inlet-side”. • Select the Named Selections in the Outline to highlight them.

  20. Named selection - outlets • Name the outlet “outlet”.

  21. Named selection – wall-pipe • Select the main pipe wall and name it “wall-pipe”.

  22. Update mesh • Select Mesh in the Outline. • Expand Sizing. • Change Use Advanced Size Function to “On: Proximity and Curvature”. • Set Min Size to 0.01. • Click Update. • Expand Statistics. • Shows ~51k elements.

  23. Display mesh section (1/2) • Click new Section Plane icon. • Draw a line on the screen.

  24. Display mesh section (2/2) • Click the pyramid icon under Section Planes. • Move the blue slider box to change the position of the plane. • Click the dashed part of the line to switch sides. • Click the solid part of the line to just get the single plane. • Uncheck the Section Plane to get back to the regular view.

  25. Launch FLUENT • Close Meshing. • In WB, right-click Setup cell, select Edit. • Opens FLUENT Launcher. • Click Ok to launch FLUENT.

  26. FLUENT model setup • Models: Energy On. • Materials: change water to “Polygoopelyne”. Density 1100 kg/m3; Cp 4000 j/kg-k; Thermal conductivity 0.5 w/m-k; viscosity 1 kg/m-s. • Inlet-main: 0.1 m/s; thermal: temperature 300K. • Inlet-side: 0.1 m/s; thermal: temperature 350K.

  27. FLUENT – output parameter • Boundary Conditions → Click Parameters • Create → Surface Integrals. • Area Weighted Average → inlet-side → Static Pressure. • Save Output Parameter → Name = pressure-side-inlet → OK → Close.

  28. FLUENT - calculation • Run calculation: 70 iterations. • Calculate (may have to click Calculate button twice). • Close FLUENT. • To see the Table of Design Points: • Double click Parameter Set. • View → Table. • Update project to fill in the value for the pressure inlet parameter.

  29. CFD-Post - Contour • In WB, right click on Results. Edit. • This opens CFD-Post. • Insert a contour: • Locations: inlet-main, inlet-side, outlet, symmetry, wall-fluid. • Variable: Static temperature. • # of Contours: 20. • Apply.

  30. Expressions • Insert two new expressions using CEL. • Average temperature at outlet: Tave Out = massFlowAve(Static Temperature)@outlet • Temperature standard deviation at outlet: Tstdout = sqrt( massFlowAve( (Static Temperature – Tave Out)^2)@outlet) • Right-click on Tstd Out under Expressions on Expressions tab and select “Use as Workbench Output Parameter” • Quit CFD-Post.

  31. Save project • Save the project. • In WB File → Save as → chemical-mixer.wbpj.

  32. Duplicate system • Right-click on “Fluid Flow (FLUENT)”. • Click Duplicate. • Name the new system “Chemical Mixer – Long Inlet”.

  33. Change inlet pipe length • Double click on Parameter Set. • View → Table. • Change the value of P3–Extrude1.FD1 to 0.1 (from 0.05). • Update Project. • Click Show Progress to show the progress during the calculation.

  34. Update project • When the calculation is done (<2 minutes), show the design point table. • The pressure at the side inlet and the temperature standard deviation at the outlet are shown for the two different pipe lengths.

  35. CFD-Post – load both result sets • Drag cell A5 (Solution) to cell B6 (Results). • Double-click cell B6 (Results) to open CFD-Post with both sets of results loaded.

  36. CFD-Post – case comparison • Double click Case Comparison. • Check Case Comparison Active. • Check Use absolute value of differences. • Quit CFD-Post.

  37. Save project • In WB → File → Save As → chemical-mixer-2-calculations.wbpj.

  38. Optional – design point analysis • Optional demo. Create a table with design points for the system using input parameters to FLUENT and output parameters calculated with CFD-Post. • Starting point: the system saved as “chemical-mixer.wbpj”. • In WB: File →“chemical-mixer.wbpj”.

  39. Input parameter in FLUENT • Setup → Edit • Boundary condition: inlet-side • Velocity Magnitude; new input parameter. Name: velocity-side. Current value 0.1 m/s. • Close FLUENT.

  40. Add design points • Add additional design points as shown in the screenshot. • Note: to save the results for each design point, check the checkbox in the Exported column.

  41. Solve Parametric Analysis (2) • Right-click on Solution cell A5 and select Clear Generated Data (may not be necessary in release version). • Click on “Update All Design Points” button from toolbar. • Workbench solves all design points sequentially. • Output parameter values* are displayed in the Table of Design Points as each run is completed.

  42. Save project • In WB → File → Save As → chemical-mixer-five-calculations.wbpj • Demonstration is complete.

More Related