1 / 23

Post- processing

Post- processing. J.Cugnoni , LMAF/EPFL, 2012. Finite element « outputs ». Essential variables: Displacement u , temperature T find u such that : K u = f Natural variables : Stress s , heat flux q

brede
Télécharger la présentation

Post- processing

An Image/Link below is provided (as is) to download presentation Download Policy: Content on the Website is provided to you AS IS for your information and personal use and may not be sold / licensed / shared on other websites without getting consent from its author. Content is provided to you AS IS for your information and personal use only. Download presentation by click this link. While downloading, if for some reason you are not able to download a presentation, the publisher may have deleted the file from their server. During download, if you can't get a presentation, the file might be deleted by the publisher.

E N D

Presentation Transcript

  1. Post-processing J.Cugnoni, LMAF/EPFL, 2012

  2. Finiteelement « outputs » • Essential variables: • Displacementu, temperature T findu suchthat: Ku = f • Natural variables : • Stress s, heat flux q • Directlyrelated to (derivatives of) essential variables by the constitutive relationship in linearproblems • Derived variables : • Likestrain = u, strainenergydensity, enthalpy

  3. FE results: type & localization • Data types: • Scalars (T): 1 component • Vectors (u): 3 components + magnitude • 2ndordertensors (s): 6 components if symm. + invariants (von Mises, max. principal, hydrostatic) • Localization: • Unique Nodal values • Element Nodal values • Gauss (integration) points values • Elementcentroid

  4. Nodal displacement u (unique nodal val., essential var.) Unique Nodal value Shape functions and derivatives are only evaluated at integ. pts Shape functions & derivatives at integration pt of the element => B matrix Strain tensor at integration pt e = eBu Element Integration pt Displacement – Strain post processing

  5. Stress calculation at integration pts (linear elasticity) Strain tensor at integration pt i of element e: eei = eBeu Element Integration pt Constitutive relationship of element e => eC matrix Element-wise constitutive relation Stress tensor at integration pt i of element e: esi = eCeei Element Integration pt

  6. From integration pts to unique nodal values Stress tensor at integration pt i of the element e: esi Element Integration pt Shape functions or other extrapolation functions Stress tensor at nodal pt j of the element e: esj Element Nodal value Weighted (or conditionnal)averaging Stress tensor at nodal pt kof the global mesh: sk Unique Nodal value

  7. FE results in Abaqus • Field output: • A snapshot of the values at all points in the model for a giventime • History output: • A « time curve » for a single variable at a given point over time • In STEP module: • Specifywhich variables must becomputed in field output & history outputs • Can specify a « frequency » to reduce the output size • For history output, youneed to define a « set » to extract time evolution of given points / elements

  8. How to: specify non-default field / history outputs • Example: • open thermoMecaExo1Correct.cae • Select to Model-1-Transient • In Step module: • Edit existing Field output: • Add all Energy outputs, add Forces-> NFORC • Add Thermal outputs NFLUX & HFLA (heat flux * area) • History outputs: • Tool -> Set -> Create : create a set of points for history output • Create a new history output • Domain=Set, Output: Thermal->NT (nodal temperature) • Run the Job « thermoMecaTransient » Video: PostProDemo1.swf

  9. FE result visualization in Abaqus • Field outputs: • Select in Results -> Field outputs • Select the desired output time (Step & Frame) • Contour plot: • colormap + deformedshape • Symbol plot: • to display vectors or principal tensor components • Otherfeatures: • Cutting planes, display groups • A lot of options to customize display

  10. Result localization in Abaqus • Abaqus Standard solver stores onlynecessaryresults in ODB files: • Essential variables : unique nodal values • Natural variables: onlyatintegration points • Derived variables: localizedwhere in makessense • Abaqus CAE / visualization module can « extrapolate » someresultsatother locations • Example: evaluate unique nodal stresses fromintegration points • You can control the extrapolation in Results -> Option. • Use view« discontinuities » to identify « strong gradient » (=lowaccuracy) regions of yourmesh

  11. How to: visualize 3D fields • Example (open thermoMecaTransient.odb): • Contour plots of stress field, select time = 2000 s: • Select Mises, S33, Max. Principal components • Change Visualization options (deformation scale factor, colormap range, edges) • Cutting plane • Results Options (select Mises stress): • Disable averaging, look at element nodal values, notice the discontinuities. • Enable averaging, change the averaging threshold (0% -> 100%) • Display discontinuities, notice regions of large discontinuities: sharp corners = stress singularities !! • Symbol plot: • Use display group to isolate a region • View principal stress tensor and displacements Video PostProDemo2.swf

  12. Extracting values atnode / element • Select Field output, activate Contour plot • Use Tools->Query->Probe Value • Select Probe = Element or Probe = Node • Select result localization (for elements only) • Integration pts, Centroid, Element nodal • Activate the desired results in the table • Pick a node / element to add it to the list • Can write the table values to a text file: write

  13. How to: extract values atselected points • Example: • Extract different stress values (int. pt, elem. nodal, averaged nodal) at a given point Video: PostProDemo3.swf

  14. Extracting curves in Abaqus • Path = spatial curve to « cut the model »: • Use Tools -> Path -> Create to generate • Generation method: • Node list: pick nodes to define a polyline • Point list: enter coordinates of polyline vertices • Edge list: select element edges = efficient !! • Circular: select points to generate a circle • To plot / save the curve: • Use Tools -> XY data -> Create • Select source = Path • Choose the path • choose configuration = « undeformed » • activate include intersection • Generate the curve & save it for later use

  15. How to: extract a 2D curvealong a path • Example: • Define a linear path based on 2 nodes • Define a path along edges with « feature edge » or « shortest distance » option • Define a circular path by 3 points • Extract curves of Mises Stress distribution along each path, save XY data • Plot all XY curves Video: PostProDemo4.swf

  16. Extracting curves in Abaqus • Time evolution curves : • From Field outputs: • Use Tools -> XY data -> Create • Choose source = Field Output • Select result localization (integ pt, nodal, …) • Select result to extract • Pick elements or nodes from 3D view • Plot and save if necessary • From History outputs: • Use Tools -> XY data -> Create • Choose source = History output • Select the desired history output, plot and save

  17. How to: extract a time-evolutioncurve • Example: • Extract time evolution curves of the temperature at some nodes • Extract time evolution curves of the Mises stress at for different type of result localization • Plot all XY curves Video: PostProDemo5.swf

  18. Exporting data from Abaqus • Exporting field outputs • If needed, isolate a region of interest with Display Group • Use Report -> Field Output • Select the localization & type of the result • Select output file & check append / overwrite • Select Data: all data, column totals, statistics?

  19. Exporting data from Abaqus • Exporting XY curves • Create XY data and save it • Use Report -> XY • Select the XY curves • Select output file & check append / overwrite • Select Data: all data, column totals, statistics?

  20. How to: export data to text files • Example: • Use Report-> Field Output to extract the min, max and average nodal temperature in a Text file • Create a XY curve of the time evolution of the temperature at one point and export it to another text file Video: PostProDemo6.swf

  21. Extracting images & movies • Image capture / printing: • File -> Print • Choose Destination = Printer or File • If File, choose format (PNG for example) and file name • Movies: • Enter an animation mode: • Animate -> Time History / Scale Factor / Harmonic • Use Animate -> Save As to generate movie • Select destination file and format • Set Options to choose the level of compression • Choose display option (background ?) • Set frame rate to ~5 image/s

  22. How to: capture images and animations • Example: • Extract an image of Mises stress field at t=2000s showing the min & max values • Extract a movie of the time evolution of the temperature in the model Video: PostProDemo7.swf

  23. Advanced post-processing • Changingcoordinate system: • Create a coordinate system (for examplecylindrical) • In Result -> Options: • choose Transformation, User defined • Pick the coordinate system to use for post processing • Calculatenew fields: • If necessary, create a new coordinate system: Tools -> Coord. System -> Create • Run Tools -> Create Field outputs -> Fromfields • Pick a time: Step & Increment • Enter an expression in the « calculator »: • Pickoperators & operands (fields) in the list • The new resultwillbe « save » in memoryonly in a temporaryStepcalled « Session Step » • You can use thistool to evaluatequantities in differentcoordinatesystems (for example stress in cylindricalcoordinates)

More Related